XY Datum Offset

This section is for useful tips and tricks for Aspire
Post Reply
User avatar
mezalick
Vectric Wizard
Posts: 2517
Joined: Mon Nov 03, 2008 9:07 am
Model of CNC Machine: Camaster Cobra
Location: Philadelphia, PA USA
Contact:

XY Datum Offset

Post by mezalick »

Greeting All,
I'm just going thru a few items in the software and I realized I've never used the XY Datum Offset....Imagine that.....
So it got me thinking about when and why to use it......
I came up empty..
So my question is, when is it appropriate to use the XY Datum Offset..
I'm sure there are plenty of good reasons otherwise it wouldn't be included in the software..

Looking forward to your ideas.
Thanks in advance.
Michael
Michael Mezalick
https://carveddetails.com
mm@mezalick.com

User avatar
TReischl
Vectric Wizard
Posts: 3154
Joined: Thu Jan 18, 2007 6:04 pm
Model of CNC Machine: 8020 Build 48X36X10 RP 2010 Screenset
Location: Leland NC

Re: XY Datum Offset

Post by TReischl »

One that comes to mind is that a part you are going to cut already has a hole cut in it. You want to use that hole to set the zero of the program.

Another is that you have a fixture that has a datum hole in it that you use for zero.

I dunno though, in about 12 years of using this software I have never found I needed to use it. ::::shrug:::::

Edit: On the mini mill I have an edge finder that I use quite often to find the center of a hole and then I use that to perform other operations after setting the DRO's. But on the router the spindle is way too fast to use that tool.
"If you see a good fight, get in it." Dr. Vernon Jones

User avatar
Leo
Vectric Wizard
Posts: 3009
Joined: Sat Jul 14, 2007 3:02 am
Model of CNC Machine: 1300 x 1300 x 254 Chinese Made
Location: East Freetown, Ma.
Contact:

Re: XY Datum Offset

Post by Leo »

I don't use it either - BUT

It would be a good point to have a "park" position away from the XY zero point so I can load/unload the part with the spindle out of the way.

I often just edit the G-Code to do that for me.
Imagine the Possibilities of a Creative mind

www.leosworkshop.com

ger21
Vectric Wizard
Posts: 1529
Joined: Sun Sep 16, 2007 2:59 pm
Model of CNC Machine: Custom DIY
Location: Shelby Township, MI, USA
Contact:

Re: XY Datum Offset

Post by ger21 »

I use it with our Morbidelli, which has a backwards Y axis from standard.
I set the Y offset to -49, and make the stock 49" high. This puts zero in the back with negative Y values in the front. I invert the Y values to positive in the post.

EDIT:

While double checking this, I realized that I can get the same thing by selecting back left for the origin and disabling the offset. :shock:
Lots of different ways to do the same thing. :)
Gerry - http://www.thecncwoodworker.com

User avatar
adze_cnc
Vectric Apprentice
Posts: 811
Joined: Sat Jul 27, 2013 10:08 pm
Model of CNC Machine: AXYZ 4008
Location: Vancouver, BC, Canada

Re: XY Datum Offset

Post by adze_cnc »

You need to fool the software into believing you have a larger piece of material than you actually have so it will calculate finishing paths properly? viewtopic.php?f=2&t=31634&p=228815#p228815

I don't often use it but it does come in handy when it is needed.

User avatar
mezalick
Vectric Wizard
Posts: 2517
Joined: Mon Nov 03, 2008 9:07 am
Model of CNC Machine: Camaster Cobra
Location: Philadelphia, PA USA
Contact:

Re: XY Datum Offset

Post by mezalick »

Thanks Gents..

Steven,
It was your post that I saw that started me on this issue...Thanks for posting it.
Ger21,
Three options for everything I always say..LOL
Leo,
You can park the router by setting the "Home / Start Position" in the material setup window on the toolpath side,,if your PP is setup for it.
TReischl,
That's a good example, thanks


Michael
Michael Mezalick
https://carveddetails.com
mm@mezalick.com

User avatar
IslaWW
Vectric Wizard
Posts: 1285
Joined: Wed Nov 21, 2007 11:42 pm
Model of CNC Machine: The Ultimate Woodworking Machine
Location: Marquette, MI, USA

Re: XY Datum Offset

Post by IslaWW »

I only use offsets in one way... To provide an intuitive drawing field when designing for my SideWinder CNC Wood lathes.
Setup.JPG
Gary Campbell
CNC Technology & Training
The Ultimate Woodworking Machine
GCnC411 (at) gmail.com

User avatar
mezalick
Vectric Wizard
Posts: 2517
Joined: Mon Nov 03, 2008 9:07 am
Model of CNC Machine: Camaster Cobra
Location: Philadelphia, PA USA
Contact:

Re: XY Datum Offset

Post by mezalick »

Make Sense Gary,,,,Thanks
~M
Michael Mezalick
https://carveddetails.com
mm@mezalick.com

4DThinker
Vectric Wizard
Posts: 1304
Joined: Sun Sep 23, 2012 12:14 pm
Model of CNC Machine: CNC Shark Pro

Re: XY Datum Offset

Post by 4DThinker »

I almost alway use it. I set X and Y value to 1/2 the diameter of the bit I'll be using first. Either may need to be a negative value depending on which corner I've chose. What it makes easy is zeroing X and Y by sneaking the bit up to the relative edge of the board until a piece of paper is trapped against the edge by the bit. I'll jog close, then use a .005" step which is also how thick paper often is. I find this much more accurate than trying to zero a bit on the center of a board. You would be surprised by how much off my students can be when asked to mark the center of their boards. When I'm starting a job with a V-bit then I skip the offset and just use the corner. I visually align the tip of the bit with the board corner.

4D

KeithW
Vectric Craftsman
Posts: 116
Joined: Sun Jun 08, 2014 3:13 am
Model of CNC Machine: Probotix Meteor, Aspire 8.014
Location: Red Deer, AB

Re: XY Datum Offset

Post by KeithW »

When I'm starting a job with a V-bit then I skip the offset and just use the corner. I visually align the tip of the bit with the board corner.
I'll do this for any bit. If I need to zero off on the corner or the center, I just slip a v-bit in and center, then put in the bit I'm using and then set the z height. Seems to work as good a any...

User avatar
rscrawford
Vectric Wizard
Posts: 967
Joined: Mon Jan 17, 2011 6:49 pm
Model of CNC Machine: CAMaster Cobra 408 ATC, ShopSabre IS408
Location: Wetaskiwin, Alberta
Contact:

Re: XY Datum Offset

Post by rscrawford »

When I’m using the cnc to cut on a lathe or an indexer, I want the xy datum to be in the centre of my material set up in the x axis but at the bottom in the y axis. So I choose the xy datum for the bottom left and then offset it half my material width.
Russell Crawford
http://www.cherryleaf-rustle.com

Will Williamson
Vectric Craftsman
Posts: 188
Joined: Sat Apr 26, 2008 2:45 pm
Model of CNC Machine: Thermwood CS-45 5 x 10
Location: Capac, Michigan
Contact:

Re: XY Datum Offset

Post by Will Williamson »

A lot of times, when I get dxf file, from a new client, the file, will import, with that box checked.
If you are not careful, you will over look that check box.
You will soon learn about that offset.
Will Williamson willcnc.com willmade.com
Williamson Lumber & Millwork Inc.
Capac, Michigan

Post Reply