Non flat material setup- can it be done in Aspire?
-
- Posts: 5
- Joined: Mon Nov 08, 2021 1:28 am
- Model of CNC Machine: Millright Mega VXL
Non flat material setup- can it be done in Aspire?
Hello everyone,
I am wanting to know if Aspire will allow you to define a dome shape as your material setup? I like to work with odd shapes of wood and would like to be able to carve on a non flat surface without cutting a bunch of air. Think a half round piece of firewood.
I am wanting to know if Aspire will allow you to define a dome shape as your material setup? I like to work with odd shapes of wood and would like to be able to carve on a non flat surface without cutting a bunch of air. Think a half round piece of firewood.
- Adrian
- Vectric Archimage
- Posts: 14655
- Joined: Thu Nov 23, 2006 2:19 pm
- Model of CNC Machine: ShopBot PRS Alpha 96x48
- Location: Surrey, UK
Re: Non flat material setup- can it be done in Aspire?
Depends on exactly what you're trying to do. If you want to v-carve a design or letters into an existing shaped piece of wood then if you can create a model that matches the piece of wood by scanning, probing, virtual machining etc you can do it with no air cutting.
-
- Vectric Wizard
- Posts: 1717
- Joined: Sun Sep 23, 2012 12:14 pm
- Model of CNC Machine: CNC Shark Pro, Probotix Meteor 25" x 50"
Re: Non flat material setup- can it be done in Aspire?
Each piece of firewood would likely be a different shape. Scanning each one to make a 3D model that you can map toolpaths to would be time consuming at best. You could compromise a bit and make a quick close 3D shape that matches the general shape (length/width/taper/height,etc.) of the piece. You are still stuck with only 3 axis cuts to approach, and not all toolpaths map to 3D models.
If your plan is to cut/carve a 3D shape from the 3D model you can't map the 3D cut to a 3D surface. Reducing air time at best would be by skipping the roughing toolpath and letting the finish toolpath deal with reducing the log down to your desired shape.
I generally use a larger endmill to do the roughing pass for quickest reduction before using a smaller ball end bit for the finishing pass. Tapered ball noses are a bit more stout than straight ones and can usually deal with remaining rough cut material as it takes small stepovers and has a cutting edge all the way up the tapered bit sides.
4D
If your plan is to cut/carve a 3D shape from the 3D model you can't map the 3D cut to a 3D surface. Reducing air time at best would be by skipping the roughing toolpath and letting the finish toolpath deal with reducing the log down to your desired shape.
I generally use a larger endmill to do the roughing pass for quickest reduction before using a smaller ball end bit for the finishing pass. Tapered ball noses are a bit more stout than straight ones and can usually deal with remaining rough cut material as it takes small stepovers and has a cutting edge all the way up the tapered bit sides.
4D
- jfederer
- Vectric Wizard
- Posts: 368
- Joined: Tue Nov 27, 2018 1:09 am
- Model of CNC Machine: CanCam D23M
- Location: Horton Township Ontario Canada
- Contact:
Re: Non flat material setup- can it be done in Aspire?
In a way, yes. For my "Harsh Mistress" project -> viewtopic.php?f=29&t=40675 I wanted the lunar topography to map to the diameter of the moon. That way the short Lunar horizon would be obvious. I did it by creating 2 Components in the Modelling tab. The first was done by creating a circle in the 2D panel with the desired diameter. Then I created a Dome shape in the Modelling tab based on that circle. I moved the Base Height down in Z until I got the spherical section I wanted above the Zero plane. This was by trial and error. Then I created a second Component with the topography, and did a simple Combine - Add operation to meld them. The end result is as you see in the Gallery.johnwebb332 wrote: ↑Sun Nov 13, 2022 2:52 amHello everyone,
... define a dome shape as your material setup?
I'm currently finishing a similar second project based on "Land", the single continent in Robert J Sawyer's "Quintaglio Ascension" series. I'll be posting that to the gallery later this week.
Joe Federer
www.fabrikisto.com incl. Tailmaker software
www.federer.ca
www.fabrikisto.com incl. Tailmaker software
www.federer.ca
-
- Vectric Craftsman
- Posts: 188
- Joined: Fri Apr 04, 2014 2:21 am
- Model of CNC Machine: Axiom AR4Pro+ and AR8Pro+
- Location: Edmonton, Alberta, Canada
Re: Non flat material setup- can it be done in Aspire?
I think that the replies given thus far aren't what the OP was after.
I think that they want to set up the work area to NOT be a plane/cube, but to be a shape of their choosing (ie the log shape he mentions, so half of a tube, split lengthwise, flat side down) so that Aspire doesn't machine the non-existent "shoulders" on the roughing pass.
Other's (including myself) have asked about a similar feature (I can't remember the technical term... adaptive machining, maybe) to reduce the amount of machining time on oddly shaped blanks. Some (very) highend CAM programs apparently have the capability, but it appears to a bridge too far for Aspire (at the moment, anyway).
I suppose if people keep asking, and it's feasible (and cost-effective), Vectric might implement such a capability.
Allan
I think that they want to set up the work area to NOT be a plane/cube, but to be a shape of their choosing (ie the log shape he mentions, so half of a tube, split lengthwise, flat side down) so that Aspire doesn't machine the non-existent "shoulders" on the roughing pass.
Other's (including myself) have asked about a similar feature (I can't remember the technical term... adaptive machining, maybe) to reduce the amount of machining time on oddly shaped blanks. Some (very) highend CAM programs apparently have the capability, but it appears to a bridge too far for Aspire (at the moment, anyway).
I suppose if people keep asking, and it's feasible (and cost-effective), Vectric might implement such a capability.
Allan
- scotttarnor
- Vectric Wizard
- Posts: 944
- Joined: Fri Aug 30, 2019 11:40 pm
- Model of CNC Machine: Piranha XL , Shark HD520
- Location: La Crosse WI
Re: Non flat material setup- can it be done in Aspire?
Like in this post?
viewtopic.php?f=29&t=38704
viewtopic.php?f=29&t=38704
Scott T
@scottscnc
@scottscnc
-
- Posts: 5
- Joined: Mon Nov 08, 2021 1:28 am
- Model of CNC Machine: Millright Mega VXL
Re: Non flat material setup- can it be done in Aspire?
Hi Allan,ZipperHead55 wrote: ↑Tue Nov 15, 2022 3:09 amI think that the replies given thus far aren't what the OP was after.
I think that they want to set up the work area to NOT be a plane/cube, but to be a shape of their choosing (ie the log shape he mentions, so half of a tube, split lengthwise, flat side down) so that Aspire doesn't machine the non-existent "shoulders" on the roughing pass.
Other's (including myself) have asked about a similar feature (I can't remember the technical term... adaptive machining, maybe) to reduce the amount of machining time on oddly shaped blanks. Some (very) highend CAM programs apparently have the capability, but it appears to a bridge too far for Aspire (at the moment, anyway).
I suppose if people keep asking, and it's feasible (and cost-effective), Vectric might implement such a capability.
Allan
You hit the nail on the head. That is exactly what I was trying to ask.
I have figured out that if I start out with a block, then create my first model as the actual shape of the workpiece, I can create the first roughing tool path to cut it to the actual shape I want to start with. I then create my "real" roughing tool path to actually start making my cut.
By creating the first roughing cut, essentially fools the system into thinking it has already cut it into that shape.
-
- Vectric Craftsman
- Posts: 188
- Joined: Fri Apr 04, 2014 2:21 am
- Model of CNC Machine: Axiom AR4Pro+ and AR8Pro+
- Location: Edmonton, Alberta, Canada
Re: Non flat material setup- can it be done in Aspire?
I think I am following what you are saying and will have to try this out. I think I tried it in the past but went about it the wrong way. If I recall the problem I had was that I didn't allow for much tolerance between my 2 roughing passes (the "fake" one and then the real one) and I didn't want to risk damaging a smaller tapered ball nose bit. If I substitute a larger bit (1/4" ball nose, for example), and minor discrepancies (deeper than anticipated cut due to real world conditions) the larger bit will deal with it easily.johnwebb332 wrote: ↑Wed Nov 16, 2022 12:58 pm
Hi Allan,
You hit the nail on the head. That is exactly what I was trying to ask.
I have figured out that if I start out with a block, then create my first model as the actual shape of the workpiece, I can create the first roughing tool path to cut it to the actual shape I want to start with. I then create my "real" roughing tool path to actually start making my cut.
By creating the first roughing cut, essentially fools the system into thinking it has already cut it into that shape.
Thanks for the idea, and I'll have to try it out when I have time.
Allan
- dealguy11
- Vectric Wizard
- Posts: 2487
- Joined: Tue Sep 22, 2009 9:52 pm
- Model of CNC Machine: Anderson Selexx 510,24x48 GCnC/WinCNC
- Location: Henryville, PA
Re: Non flat material setup- can it be done in Aspire?
John - Can you explain what you mean by your "real" roughing pass? As far as I know, none of the Aspire toolpath types remember what was cut before, so making 2 roughing toolpaths would not result in the second one only cutting what the first didn't cut. Is your "real" path actually a finishing toolpath with a large bit? In that case you don't need the first roughing pass, as the finishing path has no idea what was or wasn't cut before.
Steve Godding
Not all who wander (or wonder) are lost
Not all who wander (or wonder) are lost
- adze_cnc
- Vectric Wizard
- Posts: 4373
- Joined: Sat Jul 27, 2013 10:08 pm
- Model of CNC Machine: AXYZ 4008
- Location: Vancouver, BC, Canada
Re: Non flat material setup- can it be done in Aspire?
I think Adrian's question still stands. It may well be that you won't need to model the material and can get by with a rectilinear material block in the software—and a smaller one than the actual material at that.johnwebb332 wrote: ↑Wed Nov 16, 2022 12:58 pmI have figured out that if I start out with a block, then create my first model as the actual shape of the workpiece...
As dealguy mentioned Roughing toolpaths don't remember any thing. The only 3D toolpath that remotely "remembers" what has been cut is the 3D Finishing toolpath when using "rest" machining.
- ohiolyons
- Vectric Wizard
- Posts: 1710
- Joined: Wed May 27, 2009 7:16 pm
- Model of CNC Machine: Laguna IQ
- Location: Kettering, Ohio
Re: Non flat material setup- can it be done in Aspire?
On the odd shapes of wood comment there is a work around.
Say you material is L shaped.
Make you material big enough to fit the its shape.
Draw a vector on the material that corresponds to the actual shape of your material.
Position your model within that vector.
Now on Machine Limit Boundary, pick Selected Vector(s).
Doesn't help much with your dome issue, but does on odd shaped materials.
Say you material is L shaped.
Make you material big enough to fit the its shape.
Draw a vector on the material that corresponds to the actual shape of your material.
Position your model within that vector.
Now on Machine Limit Boundary, pick Selected Vector(s).
Doesn't help much with your dome issue, but does on odd shaped materials.
John Lyons
CNC in Kettering, Ohio
CNC in Kettering, Ohio
-
- Posts: 5
- Joined: Mon Nov 08, 2021 1:28 am
- Model of CNC Machine: Millright Mega VXL
Re: Non flat material setup- can it be done in Aspire?
I am currently using VCARVE Pro, I am asking about Aspire in hopes it will provide these abilities and if so would be worth the price.dealguy11 wrote: ↑Wed Nov 16, 2022 6:53 pmJohn - Can you explain what you mean by your "real" roughing pass? As far as I know, none of the Aspire toolpath types remember what was cut before, so making 2 roughing toolpaths would not result in the second one only cutting what the first didn't cut. Is your "real" path actually a finishing toolpath with a large bit? In that case you don't need the first roughing pass, as the finishing path has no idea what was or wasn't cut before.
That said, I was able to create a second roughing path to apply a rough cut my dome shape (cut using the first rough cut virtually) and then a finish cut applying much greater detail.
If the program does not remember what it cut previously, how do you account for not having to remove all the rough cut material in every toolpath with sequencially smaller tools?
I am going to try and prove this out shortly but the day job keeps getting in the way.
- adze_cnc
- Vectric Wizard
- Posts: 4373
- Joined: Sat Jul 27, 2013 10:08 pm
- Model of CNC Machine: AXYZ 4008
- Location: Vancouver, BC, Canada
Re: Non flat material setup- can it be done in Aspire?
If we are strictly talking about the two 3D machining toolpaths “Rough Machining” and “Finish Machining” then:johnwebb332 wrote: ↑Sat Nov 19, 2022 5:56 pmIf the program does not remember what it cut previously, how do you account for not having to remove all the rough cut material in every toolpath with sequencially smaller tools?
Finishing Machining has the ability to specify multiple bits and within the running of that specifically created toolpath each bit “remembers” the material that was removed before it. But, if you create a Finish Machining toolpath with, say, a 1/2” and a 3/8” bit then create a second Finish Machining toolpath with a 1/4” and 1/8” bit then the 2nd toolpath will have no idea that the first toolpath removed any material.
Rough Machining toolpaths only have one bit available. And again if you create two Rough Machining toolpaths netiher of them will know what the previous one did.
What I think might be happening here that is confusing others is that you are creating a Finish Machining toolpath with mutliple tools and calling the first tool or two a “virtual roughing” toolpath. Whereas others hearing the term roughing toolpath are associating it with a Rough Machining toolpath.
-
- Vectric Wizard
- Posts: 772
- Joined: Sat Jan 09, 2010 7:28 am
- Model of CNC Machine: cnc mako shark ext bed with HD 5 gantry
- Location: Buffalo,NY
Re: Non flat material setup- can it be done in Aspire?
I have done a couple on a log. Take couple pics of log, the length, width, side view and measure it. Bring it in aspire create a model of it and take a 3D mode and add to it, or add lettering to it.
Tony
Tony
What will matter is not what you bought but what you built; not what you got, but what you gave
-
- Vectric Wizard
- Posts: 772
- Joined: Sat Jan 09, 2010 7:28 am
- Model of CNC Machine: cnc mako shark ext bed with HD 5 gantry
- Location: Buffalo,NY
Re: Non flat material setup- can it be done in Aspire?
A few more pics on a log.
What will matter is not what you bought but what you built; not what you got, but what you gave