projecting toolpaths onto 3D model
-
- Posts: 40
- Joined: Sat Mar 05, 2022 5:55 am
- Model of CNC Machine: Heliner 1325M
projecting toolpaths onto 3D model
I am having some trouble projecting my vcarve onto an irregular surface. Would love some help!
I'm using the Regular Grid Importer gadget to make the model from a point cloud (generated by a probe).
This is what my preview looks like on a flat surface, and is correct: This is what my preview looks after I project the vcarve toolpaths onto my 3d model. When the machine cuts it looks like this - waay too deep into the material: I'm not sure whether I have my settings correct. Perhaps I need to adjust the distance the model sits above the material as well (in material setup)? Here is my point cloud: Thanks!
I'm using the Regular Grid Importer gadget to make the model from a point cloud (generated by a probe).
This is what my preview looks like on a flat surface, and is correct: This is what my preview looks after I project the vcarve toolpaths onto my 3d model. When the machine cuts it looks like this - waay too deep into the material: I'm not sure whether I have my settings correct. Perhaps I need to adjust the distance the model sits above the material as well (in material setup)? Here is my point cloud: Thanks!
-
- Posts: 40
- Joined: Sat Mar 05, 2022 5:55 am
- Model of CNC Machine: Heliner 1325M
Re: projecting toolpaths onto 3D model
Theoretically the bottom left of my material should be 0 on the z axis. This is the point to which all the positive and negative z axis points in the point cloud are relative.
Perhaps I'm totally wrong, but my theory is that the way this 3D model projection works is by making the highest z axis point on the model, 0, and working backwards from there, which is creating a negative z axis offset.
Perhaps I'm totally wrong, but my theory is that the way this 3D model projection works is by making the highest z axis point on the model, 0, and working backwards from there, which is creating a negative z axis offset.
- Adrian
- Vectric Archimage
- Posts: 14544
- Joined: Thu Nov 23, 2006 2:19 pm
- Model of CNC Machine: ShopBot PRS Alpha 96x48
- Location: Surrey, UK
Re: projecting toolpaths onto 3D model
Did you run the 3D toolpath preview as well? To me it looks as I would expect if you had run the v-carve toolpath on it's own without previewing the underlying model.
If you switch to 3D View (not toolpath preview) and move the mouse over the model you can see the z height displayed on the bottom status bar. The top left is 0, bottom left is 2.26, top right is 2.6 and bottom right is 3.5, centre is about 2.5.
If you switch to 3D View (not toolpath preview) and move the mouse over the model you can see the z height displayed on the bottom status bar. The top left is 0, bottom left is 2.26, top right is 2.6 and bottom right is 3.5, centre is about 2.5.
-
- Posts: 40
- Joined: Sat Mar 05, 2022 5:55 am
- Model of CNC Machine: Heliner 1325M
Re: projecting toolpaths onto 3D model
I've gone to the 3D view and looked at the z heights. The lower left corner of the material reads a z height of -1.29mm. This should be my 0 z-height (as shown on the point cloud).
I lifted my spindle by 1.29mm and ran the code and it gave a perfect result. However, it would be great to do this within Aspire, rather than cheating.
I lifted my spindle by 1.29mm and ran the code and it gave a perfect result. However, it would be great to do this within Aspire, rather than cheating.
- Adrian
- Vectric Archimage
- Posts: 14544
- Joined: Thu Nov 23, 2006 2:19 pm
- Model of CNC Machine: ShopBot PRS Alpha 96x48
- Location: Surrey, UK
Re: projecting toolpaths onto 3D model
I guess you must have changed the position in model or some such as no point is below 0 when I do a straight import with the gadget.
-
- Posts: 40
- Joined: Sat Mar 05, 2022 5:55 am
- Model of CNC Machine: Heliner 1325M
Re: projecting toolpaths onto 3D model
Thanks for replying. Hmmm, I'm so confused.
Can you run through your process of importing the grid?
Do you need to turn it into a solid shape?
I thought I could get it to work, but I'm still having inconsistent results.
I made a larger piece that turned out pretty well but I have one in the machine at the moment that doesn't look so promising.
Can you run through your process of importing the grid?
Do you need to turn it into a solid shape?
I thought I could get it to work, but I'm still having inconsistent results.
I made a larger piece that turned out pretty well but I have one in the machine at the moment that doesn't look so promising.
-
- Posts: 40
- Joined: Sat Mar 05, 2022 5:55 am
- Model of CNC Machine: Heliner 1325M
Re: projecting toolpaths onto 3D model
This is my latest point cloud.
- Adrian
- Vectric Archimage
- Posts: 14544
- Joined: Thu Nov 23, 2006 2:19 pm
- Model of CNC Machine: ShopBot PRS Alpha 96x48
- Location: Surrey, UK
Re: projecting toolpaths onto 3D model
I just loaded it via the gadget and left it at that. I didn't do anything else to it.
-
- Posts: 40
- Joined: Sat Mar 05, 2022 5:55 am
- Model of CNC Machine: Heliner 1325M
Re: projecting toolpaths onto 3D model
Hmmm, do you position the model in the material with a 0mm gap above the model?
- Adrian
- Vectric Archimage
- Posts: 14544
- Joined: Thu Nov 23, 2006 2:19 pm
- Model of CNC Machine: ShopBot PRS Alpha 96x48
- Location: Surrey, UK
Re: projecting toolpaths onto 3D model
Don't forget that the Z values show when you hover the mouse depend on where you have the z-zero set. I always work with the z-zero at the bottom so all my z values are positive. If you work with it on the top then your z-values will be negative.
-
- Posts: 40
- Joined: Sat Mar 05, 2022 5:55 am
- Model of CNC Machine: Heliner 1325M
Re: projecting toolpaths onto 3D model
So when you say you work with the z-zero on the bottom, you mean you set it to the 'machine bed', rather than the 'material surface'?
The designs I've been cutting are working to a degree. It seems that it is lifting too high in the raised areas and then cutting too deep in the sunken areas. Do you know what could be causing this?
I am v-carving so it could be a bit settings issue...
The designs I've been cutting are working to a degree. It seems that it is lifting too high in the raised areas and then cutting too deep in the sunken areas. Do you know what could be causing this?
I am v-carving so it could be a bit settings issue...
- Adrian
- Vectric Archimage
- Posts: 14544
- Joined: Thu Nov 23, 2006 2:19 pm
- Model of CNC Machine: ShopBot PRS Alpha 96x48
- Location: Surrey, UK
Re: projecting toolpaths onto 3D model
Yes, z-zero on machine bed. The bottom dot in the Job Setup picture.
If it's cutting both too high and too low that seems a bit odd to me. I can't think off the top of my head what that could be. Hopefully someone else will chime in on this thread with some ideas.
If it's cutting both too high and too low that seems a bit odd to me. I can't think off the top of my head what that could be. Hopefully someone else will chime in on this thread with some ideas.
- martin54
- Vectric Archimage
- Posts: 7339
- Joined: Fri Nov 09, 2012 2:12 pm
- Model of CNC Machine: Gerber 48, Triac PC, Isel fixed gantry
- Location: Kirkcaldy, Scotland
Re: projecting toolpaths onto 3D model
I have never used the gadget so not sure how it works but I have projected quite a bit of stuff onto 3D models.
What's your process? Are you starting with a flat piece of stock, machining the model & then projecting the vcarve onto that model or are you starting with a pre-spaped piece of stock that already has a 3D design cut on it?
The only way I can think for it to be cutting the way you describe is if you were using a pre-shaped piece of stock & the model that has been created for that doesn't match properly.
It actually looks from your picture like a flat piece of board so I don't fully understand the project onto 3D model unless that is how the gadget works.
What's your process? Are you starting with a flat piece of stock, machining the model & then projecting the vcarve onto that model or are you starting with a pre-spaped piece of stock that already has a 3D design cut on it?
The only way I can think for it to be cutting the way you describe is if you were using a pre-shaped piece of stock & the model that has been created for that doesn't match properly.
It actually looks from your picture like a flat piece of board so I don't fully understand the project onto 3D model unless that is how the gadget works.
- adze_cnc
- Vectric Wizard
- Posts: 4325
- Joined: Sat Jul 27, 2013 10:08 pm
- Model of CNC Machine: AXYZ 4008
- Location: Vancouver, BC, Canada
Re: projecting toolpaths onto 3D model
Here’s where the process breaks down. Once the point cloud is processed into Aspire via the gadget the Z values don’t corespond on a one-to-one basis with the Z values in the model in Aspire.paorawiremu wrote: ↑Fri Oct 28, 2022 3:20 amTheoretically the bottom left of my material should be 0 on the z axis. This is the point to which all the positive and negative z axis points in the point cloud are relative.
By setting the z-zero to the material surface in Aspire and by having 0mm above the model in the Material Setup dialog on the toolpath tab you are saying to the software that whatever point(s) in the point cloud that had the largest positive Z value now have a Z of zero (i.e. the surface of the theoretical material block in Aspire),
The image below is the point cloud brought into Rhino 3D. The two points in the lower right connected by a short line segment are the highest points in the cloud. They will corespond to the material surface (Z zero) when impotted into Aspire via the gadget:
If you set the z-zero on your machine to ether of those points your file should (will) cut properly as you’ve matched the z-zero in the software to the z-zero on your surface. No need to mess around with offsets here and there.
-
- Posts: 40
- Joined: Sat Mar 05, 2022 5:55 am
- Model of CNC Machine: Heliner 1325M
Re: projecting toolpaths onto 3D model
Hi Martin54,
I have an existing surface, which can't be levelled, that has some irregularities - they are very subtle, only a few mm, but they make a difference to an engraving. I use my probe to make a surface map as a point cloud, which the gadget imports and turns into a model.
I am then projecting my design onto the 3d model so that when it cuts, it will negotiate the humps and slumps correctly.
Here is my model with the image projected on it in Aspire: The problem I am having it that the lower areas (see that dark patches), are cutting too deep, and the lighter areas cutting too high.
Hi Adze,
Thanks so much for your model. Yes, this is how I was expecting it to work. I have been lifting my z-axis and zeroing to the highest point of my material surface, but I've been calling this offsetting, rather than zero-ing it to the highest point. I've been looking at how much my original z-zero dropped to see how much to lift it.
I've been using 30degree and 45degree engraving bits, so I will experiment with a few different pieces to see if they make a difference.
I have an existing surface, which can't be levelled, that has some irregularities - they are very subtle, only a few mm, but they make a difference to an engraving. I use my probe to make a surface map as a point cloud, which the gadget imports and turns into a model.
I am then projecting my design onto the 3d model so that when it cuts, it will negotiate the humps and slumps correctly.
Here is my model with the image projected on it in Aspire: The problem I am having it that the lower areas (see that dark patches), are cutting too deep, and the lighter areas cutting too high.
Hi Adze,
Thanks so much for your model. Yes, this is how I was expecting it to work. I have been lifting my z-axis and zeroing to the highest point of my material surface, but I've been calling this offsetting, rather than zero-ing it to the highest point. I've been looking at how much my original z-zero dropped to see how much to lift it.
I've been using 30degree and 45degree engraving bits, so I will experiment with a few different pieces to see if they make a difference.