Finger Pull Profile Toolpath
-
- Vectric Apprentice
- Posts: 58
- Joined: Tue Jul 26, 2022 11:42 am
- Model of CNC Machine: BZT PFK 1607 PX
Finger Pull Profile Toolpath
I am testing to use a finger pull bit to cut a finger pull profile.
The Finger Pull Bit is intended to cut a finger pull profile, i.e. an undercut profile on the edge of a wooden panel.
Since the finger pull bit is quite large, I decided not to cut the profile in one path, but in 10 steps. This means I offset the final profile 10 times with a distance of 1mm. So, each offset is one mm from the next. As a result I got 10 toolpaths. This worked, but is somewhat inefficient as the router moves a lot around between toolpaths and it's a lot of work to make changes to toolpaths since there are 10 of them.
Is there an elegant way to easily combine the 10 toolpaths into a single toolpath?
I have set the bit as a 17mm downcut bit - in Vcarve - if anyone is interested I have already created a thread regarding this topic.
viewtopic.php?f=2&t=41066&p=298453#p298453
The Finger Pull Bit is intended to cut a finger pull profile, i.e. an undercut profile on the edge of a wooden panel.
Since the finger pull bit is quite large, I decided not to cut the profile in one path, but in 10 steps. This means I offset the final profile 10 times with a distance of 1mm. So, each offset is one mm from the next. As a result I got 10 toolpaths. This worked, but is somewhat inefficient as the router moves a lot around between toolpaths and it's a lot of work to make changes to toolpaths since there are 10 of them.
Is there an elegant way to easily combine the 10 toolpaths into a single toolpath?
I have set the bit as a 17mm downcut bit - in Vcarve - if anyone is interested I have already created a thread regarding this topic.
viewtopic.php?f=2&t=41066&p=298453#p298453
- sharkcutup
- Vectric Wizard
- Posts: 2925
- Joined: Sat Mar 26, 2016 3:48 pm
- Model of CNC Machine: Shark HD3 Pro Extended Bed with Spindle
- Location: U.S.A.
Re: Finger Pull Profile Toolpath
Yup!!!
Select all toolpaths so that they are visible then this button in red in image here. Of course they all must be using same tool for this to work. Otherwise No!!! Sharkcutup
Select all toolpaths so that they are visible then this button in red in image here. Of course they all must be using same tool for this to work. Otherwise No!!! Sharkcutup
V-Carve Pro Tips, Gadget Tips & Videos
YouTube Channel - Sharkcutup CNC
V-Carve Pro 12.004
YouTube Channel - Sharkcutup CNC
V-Carve Pro 12.004
-
- Vectric Apprentice
- Posts: 58
- Joined: Tue Jul 26, 2022 11:42 am
- Model of CNC Machine: BZT PFK 1607 PX
Re: Finger Pull Profile Toolpath
Ahh , "Create Merged Toolpath". Never used that one, apparently I've got some new stuff to watch on YouTube.
Thanks for the tip @sharkcutup !
Thanks for the tip @sharkcutup !
- adze_cnc
- Vectric Wizard
- Posts: 4374
- Joined: Sat Jul 27, 2013 10:08 pm
- Model of CNC Machine: AXYZ 4008
- Location: Vancouver, BC, Canada
Re: Finger Pull Profile Toolpath
Or… Create only one (1) toolpath. There are at least two ways to do this:
- If you don’t mind the bit travelling from left to right then right to left, etc. Connect the ends of all the vectors so that it creates a zig-zag pattern (i.e. connect every 2nd set of lines on one end then every alternate set of lines on the other end)
- if you need the cut to always travel in one direction then connect the end-point of each line to the starting point of the next deepest cutting line
- jimwill2
- Vectric Wizard
- Posts: 612
- Joined: Tue Aug 31, 2010 1:48 am
- Model of CNC Machine: CaMaster Stinger w/recoil, FTC
- Location: Parkville, Missouri
Re: Finger Pull Profile Toolpath
I would most likely create a "pocket" vector and run a pocket toolpath to cut out most of the material before I used the expensive bit to do the undercut. I would make it a little shallow and leave a little on the edge so the Finger Pull bit does all the finish work.
Jim Williams
- adze_cnc
- Vectric Wizard
- Posts: 4374
- Joined: Sat Jul 27, 2013 10:08 pm
- Model of CNC Machine: AXYZ 4008
- Location: Vancouver, BC, Canada
Re: Finger Pull Profile Toolpath
There is a pocket toolpath in the original screen-shot so perhaps that was already thought of?
-
- Vectric Apprentice
- Posts: 58
- Joined: Tue Jul 26, 2022 11:42 am
- Model of CNC Machine: BZT PFK 1607 PX
Re: Finger Pull Profile Toolpath
Hi Jim, yes this exactly what I did. First I have cut a pocket with a 8mm downcut bit that is 0.3mm shallower. I should have mentioned that.jimwill2 wrote: ↑Fri Jan 20, 2023 5:40 pmI would most likely create a "pocket" vector and run a pocket toolpath to cut out most of the material before I used the expensive bit to do the undercut. I would make it a little shallow and leave a little on the edge so the Finger Pull bit does all the finish work.
-
- Vectric Apprentice
- Posts: 58
- Joined: Tue Jul 26, 2022 11:42 am
- Model of CNC Machine: BZT PFK 1607 PX
Re: Finger Pull Profile Toolpath
Your suggestion for a zigzag pattern is interesting because I tried exactly that before writing this post, but I got an error message and didn't want to troubleshot .... but now I'm encouraged to try againadze_cnc wrote: ↑Fri Jan 20, 2023 5:28 pmOr… Create only one (1) toolpath. There are at least two ways to do this:
In both cases you must tell the profile toolpath to keep the original starting point and not try to move it so that it starts outside then moves inward.
- If you don’t mind the bit travelling from left to right then right to left, etc. Connect the ends of all the vectors so that it creates a zig-zag pattern (i.e. connect every 2nd set of lines on one end then every alternate set of lines on the other end)
- if you need the cut to always travel in one direction then connect the end-point of each line to the starting point of the next deepest cutting line
-
- Vectric Apprentice
- Posts: 58
- Joined: Tue Jul 26, 2022 11:42 am
- Model of CNC Machine: BZT PFK 1607 PX
Re: Finger Pull Profile Toolpath
Ok, if I try the zig zap pattern and use "Machine Vector" Outside/Right I get an error message. If I use Inside/Left it I don't get an error message but the 3D view shows something is not quite right.
I think my zigzag pattern is connected with no mistakes.
I think my zigzag pattern is connected with no mistakes.
- adze_cnc
- Vectric Wizard
- Posts: 4374
- Joined: Sat Jul 27, 2013 10:08 pm
- Model of CNC Machine: AXYZ 4008
- Location: Vancouver, BC, Canada
Re: Finger Pull Profile Toolpath
Ah. My presumption (not having access to the file) was that with a form tool like this that you would be drawing the path so that it follows the centre of the tool and that you would be running the profiles “on the line”. Both of my suggestion will fail when set to either in or outside the line.
- sharkcutup
- Vectric Wizard
- Posts: 2925
- Joined: Sat Mar 26, 2016 3:48 pm
- Model of CNC Machine: Shark HD3 Pro Extended Bed with Spindle
- Location: U.S.A.
Re: Finger Pull Profile Toolpath
Stephen (Adze_cnc)
Read the other Op's thread for the form tool Image and description. viewtopic.php?f=2&t=41066&p=298453#p298453
Sharkcutup
Read the other Op's thread for the form tool Image and description. viewtopic.php?f=2&t=41066&p=298453#p298453
Sharkcutup
V-Carve Pro Tips, Gadget Tips & Videos
YouTube Channel - Sharkcutup CNC
V-Carve Pro 12.004
YouTube Channel - Sharkcutup CNC
V-Carve Pro 12.004
-
- Vectric Apprentice
- Posts: 58
- Joined: Tue Jul 26, 2022 11:42 am
- Model of CNC Machine: BZT PFK 1607 PX
Re: Finger Pull Profile Toolpath
Well, my initial offsets were set up so that the machine vectors were "outside/right". ... but ackchyually "machine vectors/on the line" works fine, I'll just adapt my line work to that..adze_cnc wrote: ↑Fri Jan 20, 2023 7:28 pmAh. My presumption (not having access to the file) was that with a form tool like this that you would be drawing the path so that it follows the centre of the tool and that you would be running the profiles “on the line”. Both of my suggestion will fail when set to either in or outside the line.
Thank you for your help!