Separate Last Pass for reducing tool marks

This forum is for users to post tips and tricks they have found useful while working with VCarve Pro
Post Reply
laflippin
Vectric Craftsman
Posts: 216
Joined: Tue Jun 12, 2018 3:07 pm
Model of CNC Machine: Axiom AR 8 Pro+
Location: Cambria, CA

Separate Last Pass for reducing tool marks

Post by laflippin »

Hi Folks,
I've lately been making some small oval boxes (4" x 7") that are anywhere from 1.5" to 1.8" thick. Some of these boxes have been cut from a single piece of Douglas fir and others have been cut from homemade laminates containing Doug fir, yellowheart, walnut, purpleheart and others.

Using a 1/2" end mill with 2" of cutting depth, it is easy enough to make these boxes with a pocket cut, followed by a profile cut (using tabs). However, perhaps not too surprisingly, both the pocket cuts and especially the profile cuts are leaving vertical tool marks that need plenty of sanding to remove.

I found a brief discussion of the "Do a Separate Last Pass" function in a Vectric tutorial about Profile Toolpaths. In the tutorial it was just briefly mentioned that the Separate Last Pass function may help to reduce unwanted tool marks and the suggested Last Pass value was just 0.01" (without further explanation, or any kind of demo of an outcome).

So, I tried using this function in a profile cut and used a Last Pass value of 0.02"--I figured doubling the suggested value might be reasonable given the rather large tool marks I was seeing on my boxes. Well, that didn't seem to make any difference at all! I'm afraid I wasn't paying close enough attention at the crucial time but...I'm not even sure there was a "separate last pass" in the actual profile cut. At least, the result didn't look any different than previous examples and, so, back to one of my least favorite woodworking activities.....more sanding.

I am wondering (1) if experienced users here at the forum might be able to help me out with their experiences using the "Do a Separate Last Pass" function within the Profile Toolpath menu; i.e., what values do you use and how effective are they? (2) I was also wondering if there is any help for reducing tool marks in the deep pocket cuts I've been making. There doesn't seem to be a corresponding "Separate Last Pass" option for pocket cuts.

Thanks in advance!

User avatar
martin54
Vectric Archimage
Posts: 7339
Joined: Fri Nov 09, 2012 2:12 pm
Model of CNC Machine: Gerber 48, Triac PC, Isel fixed gantry
Location: Kirkcaldy, Scotland

Re: Separate Last Pass for reducing tool marks

Post by martin54 »

Is it tool marks where the bit plunges you are getting? if so them you might look at using leads which can help prevent this so I have read, no experience with leads or the last pass feature personally.
What bits are you using? I often find straight fluted bits leave a better finish than spiral bits on certain types of wood :lol: :lol:

laflippin
Vectric Craftsman
Posts: 216
Joined: Tue Jun 12, 2018 3:07 pm
Model of CNC Machine: Axiom AR 8 Pro+
Location: Cambria, CA

Re: Separate Last Pass for reducing tool marks

Post by laflippin »

Thanks, Martin! The tool marks are straight vertical lines where the bit plunges--especially bad where the tabs begin and end. The bit I've been using is a straight-fluted end mill, dia = 1/2".

If there is no really satisfactory answer for this issue I think maybe I'm looking at purchasing a decent table-top belt sander...maybe I should do that anyway. :|

4DThinker
Vectric Wizard
Posts: 1701
Joined: Sun Sep 23, 2012 12:14 pm
Model of CNC Machine: CNC Shark Pro, Probotix Meteor 25" x 50"

Re: Separate Last Pass for reducing tool marks

Post by 4DThinker »

Just like Martin, I'm going to recommend you look up lead-ins/outs to avoid tool marks from plunging/retracking.

4D

laflippin
Vectric Craftsman
Posts: 216
Joined: Tue Jun 12, 2018 3:07 pm
Model of CNC Machine: Axiom AR 8 Pro+
Location: Cambria, CA

Re: Separate Last Pass for reducing tool marks

Post by laflippin »

Thanks, 4D. Do you have personal experience using lead-ins/lead-outs to reduce tool marks in Profile and/or Pocket cuts? I'll look around for information on the lead-in function but would also appreciate anyone else who wants to jump in and shorten the trail on this topic.

4DThinker
Vectric Wizard
Posts: 1701
Joined: Sun Sep 23, 2012 12:14 pm
Model of CNC Machine: CNC Shark Pro, Probotix Meteor 25" x 50"

Re: Separate Last Pass for reducing tool marks

Post by 4DThinker »

When I'm cutting the perimeter of anything I always use lead-ins/outs. When I'm using anything larger than a 3/16" spiral upcut bit I also use ramping for the initial plunging of each pass.

4D

wb9tpg
Vectric Wizard
Posts: 456
Joined: Tue Sep 04, 2018 2:49 pm
Model of CNC Machine: Shapeoko 3 XL

Re: Separate Last Pass for reducing tool marks

Post by wb9tpg »

I did my own separate last pass toolpath using an offset to control the amount it cuts. It uses the same vector as pocket toolpath. My pockets are 0.59" deep and cut with multiple passes and the pocket cut is run first (conventional cut). Then the profile tool path is run next at the full depth in one pass with a 0.02" offset (climb cut). I wanted to fully control the cuts myself.

BTW: If you make lids for your boxes offset is your friend as you can control the fit of the lid to the base.
Gary Mitchell
Kentucky, USA

laflippin
Vectric Craftsman
Posts: 216
Joined: Tue Jun 12, 2018 3:07 pm
Model of CNC Machine: Axiom AR 8 Pro+
Location: Cambria, CA

Re: Separate Last Pass for reducing tool marks

Post by laflippin »

Thanks wb9tbg,

Yes, I do make lids for them and I typically do use a small offset so that the lids fit snugly, but not overly tight.

User avatar
TReischl
Vectric Wizard
Posts: 4577
Joined: Thu Jan 18, 2007 6:04 pm
Model of CNC Machine: 8020 48X36X7 RP 2022 UCCNC Screenset
Location: Leland NC

Re: Separate Last Pass for reducing tool marks

Post by TReischl »

A finish pass is the key.

If you are making tabs then lead in/out is only going to help at the start of the cut, it won't do a thing for those pesky tab tool marks.

I would not use a .02 "finish" pass. Typically I use somewhere between .005 and .010. Those marks are not as deep as they appear. On vertical walls I always use a Ramp tool path with Spiral checked. The problem is doing this with tabs. The tabs may not be strong enough to hold the piece while doing a finish cut. You will have to experiment with tab thickness to get a feel for what works. These days I am leaving tabs about .187 thick and it seems to work.

For finishing the bottom of pockets I use a .005 DOC and I set the step over to about 25% of the diameter.

For really nice work figure you are going to take a finish pass on every surface. I suppose that is why they call it a "finish" pass?

For some odd reason many of us seem to think that we should be able to take one pass on something and have a beautiful finished piece. Strange because as woodworkers we already know that surfaces require some kind of finishing after machining, usually sanding.
"If you see a good fight, get in it." Dr. Vernon Johns

User avatar
Xxray
Vectric Wizard
Posts: 2300
Joined: Thu Feb 17, 2011 8:47 am
Model of CNC Machine: CAMaster Stinger 1
Location: MI USA

Re: Separate Last Pass for reducing tool marks

Post by Xxray »

Is "separate last pass" a function of the newest aspire ? I have never heard of it. If you are just doing 1 roughing pass then naturally your finish will not be optimal.

Might be worth considering using double stick tape to eliminate the need for tabs, cure that problem at least.
Doug

User avatar
Adrian
Vectric Archimage
Posts: 14544
Joined: Thu Nov 23, 2006 2:19 pm
Model of CNC Machine: ShopBot PRS Alpha 96x48
Location: Surrey, UK

Re: Separate Last Pass for reducing tool marks

Post by Adrian »

Separate last pass has been around for a few versions now in both Aspire and VCarve. It's an option on the profile toolpath.

User avatar
Rcnewcomb
Vectric Archimage
Posts: 5886
Joined: Fri Nov 04, 2005 5:54 am
Model of CNC Machine: 24x36 GCnC/WinCNC with ATC
Location: San Jose, California, USA
Contact:

Re: Separate Last Pass for reducing tool marks

Post by Rcnewcomb »

Check the "Show advanced toolpath options" box to have the "Do Separate Last Pass" section appear
LastPass.JPG
- Randall Newcomb
10 fingers in, 10 fingers out, another good day in the shop

User avatar
Xxray
Vectric Wizard
Posts: 2300
Joined: Thu Feb 17, 2011 8:47 am
Model of CNC Machine: CAMaster Stinger 1
Location: MI USA

Re: Separate Last Pass for reducing tool marks

Post by Xxray »

Oh profile, I was looking at pockets. Hmm, never used that option never really had the need I guess.
Doug

User avatar
rscrawford
Vectric Wizard
Posts: 1102
Joined: Mon Jan 17, 2011 6:49 pm
Model of CNC Machine: CAMaster Cobra 408 ATC, ShopSabre IS408
Location: Wetaskiwin, Alberta
Contact:

Re: Separate Last Pass for reducing tool marks

Post by rscrawford »

Try using the spiral ramp feature for the profile cut. This does a continuous ramp cut, so there aren't any plunges. Then do a separate last pass to remove any tiny tool marks from the spiral cut.
Russell Crawford
http://www.cherryleaf-rustle.com

laflippin
Vectric Craftsman
Posts: 216
Joined: Tue Jun 12, 2018 3:07 pm
Model of CNC Machine: Axiom AR 8 Pro+
Location: Cambria, CA

Re: Separate Last Pass for reducing tool marks

Post by laflippin »

Ted and Randall, Thank you very much for your concise discussions and advice--I will be trying out your tips pretty soon and will let you know how things work out. By the way, I really am not trying to eliminate the need for finish sanding--like you, I think it is an unavoidable part of good woodworking. But, whatever I can do to reduce the need for coarse sanding to remove glaring tool marks will be very much appreciated.

Post Reply