V-Grooving Stone

This forum is for general discussion about Aspire
Post Reply
User avatar
Leo
Vectric Wizard
Posts: 4082
Joined: Sat Jul 14, 2007 3:02 am
Model of CNC Machine: 1300 x 1300 x 254 Chinese Made
Location: East Freetown, Ma.
Contact:

V-Grooving Stone

Post by Leo »

I have a potential job to "V-Groove" a compass rose into a Blue Stone paver for a customer.

I see some diamond impregnated rotary cutters out there.

Does anybody have experience v-grooving in stone?
Imagine the Possibilities of a Creative mind, combined with the functionality of CNC

User avatar
dwilli9013
Vectric Wizard
Posts: 1237
Joined: Mon Sep 30, 2013 12:45 am
Model of CNC Machine: 3 axis Self Designed Self Built
Location: Machesney Park Illinois

Re: V-Grooving Stone

Post by dwilli9013 »

Seems I remember a while back in a post someone was cutting pavers on their CNC. I guess the biggest issue was the dust goes everywhere.
I would suspect the rigidity of your machine would play a major role as well.

I myself have been wondering how a Marble tile may come out with a diamond drag bit engraving.
Just not ready to thrash my drag bit yet with a try.
D-Dub
Dwayne
Dwilli

User avatar
Rcnewcomb
Vectric Archimage
Posts: 5887
Joined: Fri Nov 04, 2005 5:54 am
Model of CNC Machine: 24x36 GCnC/WinCNC with ATC
Location: San Jose, California, USA
Contact:

Re: V-Grooving Stone

Post by Rcnewcomb »

Marble tile
Marble V-Carves very nicely.
Image
- Randall Newcomb
10 fingers in, 10 fingers out, another good day in the shop

User avatar
dwilli9013
Vectric Wizard
Posts: 1237
Joined: Mon Sep 30, 2013 12:45 am
Model of CNC Machine: 3 axis Self Designed Self Built
Location: Machesney Park Illinois

Re: V-Grooving Stone

Post by dwilli9013 »

Rcnewcomb wrote:
Marble tile
Marble V-Carves very nicely.
Image
Thanks Randall,
Was that done with a carbide V-Bit? Also feeds & Speeds if you recall.
Thanks
D-Dub
Dwayne
Dwilli

User avatar
Rcnewcomb
Vectric Archimage
Posts: 5887
Joined: Fri Nov 04, 2005 5:54 am
Model of CNC Machine: 24x36 GCnC/WinCNC with ATC
Location: San Jose, California, USA
Contact:

Re: V-Grooving Stone

Post by Rcnewcomb »

This particular piece was cut with the following settings:
PC router at 13,000 (I'd like to run slower but the PC loses too much torque at 10,000)
Feed and plunge rates of 0.1 ips (6 ipm) -- I have gone as fast as 1ips (60 ipm) on other pieces of stone. I'm sure I could have used faster feed rates if I had a better hold down system at the time. Back then I screwed down scrap wood around the marble to hold it in place. I later moved to vacuum pods.

Bit:
I used a Sears craftsman 1/2" V90. Now I'm inclined to use a CMT 3/4" V90 or 1/2" V60. I use a Gerber 1.25" V120 for some applications but haven't tried it with stone yet.

Cooling:
I held a shop vacuum nozzle near the bit which kept lots of air moving. The bit and collet were warm but not hot at the end of the run.
- Randall Newcomb
10 fingers in, 10 fingers out, another good day in the shop

User avatar
dwilli9013
Vectric Wizard
Posts: 1237
Joined: Mon Sep 30, 2013 12:45 am
Model of CNC Machine: 3 axis Self Designed Self Built
Location: Machesney Park Illinois

Re: V-Grooving Stone

Post by dwilli9013 »

Thanks Randall.

Sorry Leo I wasn't intending to hijack your thread.
D-Dub
Dwayne
Dwilli

User avatar
Leo
Vectric Wizard
Posts: 4082
Joined: Sat Jul 14, 2007 3:02 am
Model of CNC Machine: 1300 x 1300 x 254 Chinese Made
Location: East Freetown, Ma.
Contact:

Re: V-Grooving Stone

Post by Leo »

Don't be sorry.

I am thankful to be generating discussion about it.
Diamond Cutters.jpg
Has anybody used anything like this

I have used Carbide to cut marble before.
Imagine the Possibilities of a Creative mind, combined with the functionality of CNC

Jane Ndungu
Vectric Craftsman
Posts: 201
Joined: Fri Oct 31, 2014 8:14 am
Model of CNC Machine: TS1325

Re: V-Grooving Stone

Post by Jane Ndungu »

Hello Vectric,

Kindly let me know if my CNC for wood can also engrave on Marble and other material.
If yes this would be so so good.

Kind regards
Jane

Jane Ndungu
Vectric Craftsman
Posts: 201
Joined: Fri Oct 31, 2014 8:14 am
Model of CNC Machine: TS1325

Re: V-Grooving Stone

Post by Jane Ndungu »

Rcnewcomb wrote:
Marble tile
Marble V-Carves very nicely.
Image

Hello Randall,
Could you kindly let me know where you got this file from.

Thank you
Jane

User avatar
Rcnewcomb
Vectric Archimage
Posts: 5887
Joined: Fri Nov 04, 2005 5:54 am
Model of CNC Machine: 24x36 GCnC/WinCNC with ATC
Location: San Jose, California, USA
Contact:

Re: V-Grooving Stone

Post by Rcnewcomb »

Regarding Leo's original question regarding paver stones, I don't have any experience with those.
Kindly let me know if my CNC for wood can also engrave on Marble and other material.
V-Carving on Marble, limestone, or soapstone can be done with a router that can handle hardwoods. No special bits or cooling is required. Regular carbide bits work fine. Slow the feedrate down a bit from what you would normally use with a dense hardwood. Keep your pass depth fairly shallow.
Could you kindly let me know where you got this file from.
It is from the VectorArt.com Mega Collection #1, Image ID: 32809L You can purchase the individual file from them for $2.
- Randall Newcomb
10 fingers in, 10 fingers out, another good day in the shop

User avatar
Leo
Vectric Wizard
Posts: 4082
Joined: Sat Jul 14, 2007 3:02 am
Model of CNC Machine: 1300 x 1300 x 254 Chinese Made
Location: East Freetown, Ma.
Contact:

Re: V-Grooving Stone

Post by Leo »

Jane,

I have cut Marble with a Carbide V-Groove Cutter and is worked - OK, but the process was very slow and it really beat up the cutter.

The job I am asking about now is stone and a much larger project. I will be cutting into a stone 24 x 24 x 2" thick.
Imagine the Possibilities of a Creative mind, combined with the functionality of CNC

phill05
Vectric Craftsman
Posts: 181
Joined: Thu Oct 14, 2010 2:40 pm
Model of CNC Machine: Hybrid re-build
Location: Derbyshire UK

Re: V-Grooving Stone

Post by phill05 »

Leo,

Stone is more abrasive than marble what I do is grind my own cutters and use a 3 face \/ cutter 15 deg to 60 deg use plenty of water to wash away the dust to keep a clean cutting edge so it's not re-grinding the dust again, you would need to be cutting slowly DOC I work on 5mm you will tell from the sound the machine is making when you are about right for FPS as stone varies in density/hardness.
The test piece image shows the amount of dust washed out so if the machine is your pride and joy and not use to the amount of abuse or water you will put on it I would be careful.

Phill

P8292395_.jpg
head_4_.jpg
Test piece_.jpg
A person who works with his hands, his brain and his heart is an artist"
—Louis Nizer

User avatar
Leo
Vectric Wizard
Posts: 4082
Joined: Sat Jul 14, 2007 3:02 am
Model of CNC Machine: 1300 x 1300 x 254 Chinese Made
Location: East Freetown, Ma.
Contact:

Re: V-Grooving Stone

Post by Leo »

Phil - PERFECT - this is what I need to know.

Are you using carbide cutters?

What you are grinding for 3 face cutters - Carbide?

Are you using High RPM - or Low RPM on the spindle?

I will need to make some kind of water tank to capture the slurry and protect the machine.

Thank you

Do you have any further recommendations?
Imagine the Possibilities of a Creative mind, combined with the functionality of CNC

User avatar
Leo
Vectric Wizard
Posts: 4082
Joined: Sat Jul 14, 2007 3:02 am
Model of CNC Machine: 1300 x 1300 x 254 Chinese Made
Location: East Freetown, Ma.
Contact:

Re: V-Grooving Stone

Post by Leo »

I had a dremel tool carbide burr. Not the highest quality cutter, 1/8 shank. I called it a 1/8 ball nosed cutter.

I set 10,000 RPM on the spindle and feedrate at 10 IMP DOC at .01

I used a spray bottle with water and stream. Depth into stone 1/16. Just made sure the stone was well and puddles around the cutter.

I cut a small oval and it looked great.

I that tries 3 letters. The cutter failed on on letter #2 about 80% through.

I have a LOT of different cutter variations on order both Diamond impregnated and carbide blade.

At this point I am confident that cutting stone is certainly a do-able thing to do.
Imagine the Possibilities of a Creative mind, combined with the functionality of CNC

phill05
Vectric Craftsman
Posts: 181
Joined: Thu Oct 14, 2010 2:40 pm
Model of CNC Machine: Hybrid re-build
Location: Derbyshire UK

Re: V-Grooving Stone

Post by phill05 »

Hi Leo,

Sorry it took a while to get back , you found out the normal cutters soon wear out because they are too sharp for stone, I buy in carbide rod to shape up either radius end or V and grind 3 faces into them grinding them to get very little back relief making for a stronger cutting edge that does not rub off too quickly, normal carbide cutters cut work fine in marbles and resinbonds but stone needs that little bit more if you have a lot to cut then you might look at PCD (diamond)

Phill
A person who works with his hands, his brain and his heart is an artist"
—Louis Nizer

Post Reply