Trouble with a rectangle
Trouble with a rectangle
Did a search but could not locate anything that explains what I may be missing while programing a rectangle and have it cut correct in a squared off fashion
When I draw a rectangle like for a camper window it looks correct.
I then build the tool path and preview it. it looks correct in aspire.
When I send the code to Mach 3 to cut, it will make the windows with large curves in the corners and will not completely close the rectangle. It is like the V-bit comes out early. This also happens when the doors are done also
I am using a profile tool path and have also tried a v-carve, but the v-carve tries to clean out the complete inside of the window.
Small windows have come out correct, but when I have to make them larger they mess up.
I also have straight lines wrong also V-bit looks like it ramps out early.
I just know it is something simple, but I am at a loss
can anyone help??
When I draw a rectangle like for a camper window it looks correct.
I then build the tool path and preview it. it looks correct in aspire.
When I send the code to Mach 3 to cut, it will make the windows with large curves in the corners and will not completely close the rectangle. It is like the V-bit comes out early. This also happens when the doors are done also
I am using a profile tool path and have also tried a v-carve, but the v-carve tries to clean out the complete inside of the window.
Small windows have come out correct, but when I have to make them larger they mess up.
I also have straight lines wrong also V-bit looks like it ramps out early.
I just know it is something simple, but I am at a loss
can anyone help??
- FixitMike
- Vectric Wizard
- Posts: 2177
- Joined: Sun Apr 17, 2011 5:21 am
- Model of CNC Machine: Shark Pro Plus (retired)
- Location: Burien, WA USA
Re: Trouble with a rectangle
Check that you have selected the correct post processor. The wrong one can have weird effects.
Good judgement comes from experience.
Experience comes from bad judgement.
Experience comes from bad judgement.
Re: Trouble with a rectangle
I am using the same one I always use.
Mach 2/3 Arcs (inch) (*.txt)
Mach 2/3 Arcs (inch) (*.txt)
Re: Trouble with a rectangle
This is the issue.
One good rectangle and the rest are bad.
They are all programed the same. Just different sizes.
One good rectangle and the rest are bad.
They are all programed the same. Just different sizes.
- Rcnewcomb
- Vectric Archimage
- Posts: 5928
- Joined: Fri Nov 04, 2005 5:54 am
- Model of CNC Machine: 24x36 GCnC/WinCNC with ATC
- Location: San Jose, California, USA
- Contact:
Re: Trouble with a rectangle
Increase your acceleration or lower your feedrate.
See this thread on CNCzone.com: HELP Mach3 strange corner radius issue happening
See this thread on CNCzone.com: HELP Mach3 strange corner radius issue happening
- Randall Newcomb
10 fingers in, 10 fingers out, another good day in the shop
10 fingers in, 10 fingers out, another good day in the shop
Re: Trouble with a rectangle
I will give that a shot. The Thread did make sense.
-
- Vectric Wizard
- Posts: 1717
- Joined: Sun Sep 23, 2012 12:14 pm
- Model of CNC Machine: CNC Shark Pro, Probotix Meteor 25" x 50"
Re: Trouble with a rectangle
All about G61 and G64. http://linuxcnc.org/docs/2.6/html/gcode ... :G61-G61_1
-
- Vectric Wizard
- Posts: 1592
- Joined: Sun Sep 16, 2007 2:59 pm
- Model of CNC Machine: Custom DIY
- Location: Lake St Clair, MI, USA
- Contact:
Re: Trouble with a rectangle
In General Config, check "Exact Stop on Angles >" and set it to 89.
Gerry - http://www.thecncwoodworker.com
- martin54
- Vectric Archimage
- Posts: 7355
- Joined: Fri Nov 09, 2012 2:12 pm
- Model of CNC Machine: Gerber 48, Triac PC, Isel fixed gantry
- Location: Kirkcaldy, Scotland
Re: Trouble with a rectangle
Gerry I know you are an expert with mach3 so is that recommendation something that has changed over the years? Can't remember what figure it is set at but pretty sure my machine is set a lot lower than angles less than 89 degrees which was something I read on the mach support forum a few years agoger21 wrote:In General Config, check "Exact Stop on Angles >" and set it to 89.
-
- Vectric Wizard
- Posts: 1592
- Joined: Sun Sep 16, 2007 2:59 pm
- Model of CNC Machine: Custom DIY
- Location: Lake St Clair, MI, USA
- Contact:
Re: Trouble with a rectangle
It really depends on what you are doing. There is no "one size fits all" setting.
But if you're cutting mostly 90° corners, than the 89° settings works well.
But if you're cutting mostly 90° corners, than the 89° settings works well.
Gerry - http://www.thecncwoodworker.com
Re: Trouble with a rectangle
Thanks for all the Help.
I will try all suggestions tonight after work.
I will try all suggestions tonight after work.
Re: Trouble with a rectangle
Slowing down the feed rate corrected it all.
Never thought that would make that big of a difference.
Thanks everyone for the help
Never thought that would make that big of a difference.
Thanks everyone for the help
-
- Vectric Wizard
- Posts: 1592
- Joined: Sun Sep 16, 2007 2:59 pm
- Model of CNC Machine: Custom DIY
- Location: Lake St Clair, MI, USA
- Contact:
Re: Trouble with a rectangle
Slowing down is probably the least desirable fix.
Increasing acceleration is the better option, if your machine is capable of it.
Second best option is adjusting the CV controls.
Slowing down results in shorter tool life, and longer cut times.
Increasing acceleration is the better option, if your machine is capable of it.
Second best option is adjusting the CV controls.
Slowing down results in shorter tool life, and longer cut times.
Gerry - http://www.thecncwoodworker.com