beveled edge table top

[Pete Cyr]

https://www.routerbitworld.com/Freud-40 ... 40-118.htm

Of you could just use a router

[duster]

Update: For a test, I drew this as a 14" diameter circle and applied a 45 degree edge vector to cut 1.75" deep into a 2" thick piece of foam. Rough cut was with a 1/2" end mill, finish cut with a 3/8 ball nose. It cut very well with good smoothness on the bevel.

The only issue was it only cut about 1.625" deep, instead of the 1.75" I specified. Z zero was set at material surface, so I'm not sure why it didn't cut as deep as I wanted... This would be an issue when I go to cut my 40 x 60 x 2.25 oval, because I'll need to cut all the way through.

Any suggestions on what I should have done?

[4DThinker]

When using a ball nose bit and the moulding toolpath, the toolpath generator keeps the ball end tangent with the 45 degree slope. The bottom of the ball nose stopped at 1.75" but the tangent edge wasn't at the bottom of the bit. I quickly drew up a 1.75" wide/deep 45 degree line and a 3/8" circle to represent the 3/8" ball nose bit. When the circle bottom is aligned with the line bottom the tangent point is 1.6951 from the top according to Aspire. Using a smaller ballnose bit will get you closer to the bottom, but the only way to make sure the tangent edge gets to the bottom is to extend the 45 degree line down. For a 3/8" bit the line should go down (vertically) another 1.75" - 1.6951" or .0549". This will cut into your spoilboard unless you shim up your work 1/16" or so.

4D

[duster]

Ok, that makes sense. I'll have a mdf spoilboard under my walnut slab, so if I go 3/16 deeper I should be able to cut all the way through. Thanks! (I'll test this in foam before I try cutting $1200 worth of walnut...)

[duster]

Elipse test 1 15w x 10h x 2 thick preview 2D toolpath.crv

(2.9 MiB) Not downloaded yet

So I'm about to try another test to see if I can cut my beveled edge all the way through my 2" thick piece of foam
so I can get my 45 degree edge all the way to the bottom.

To enable my 3/8 ball nose bit to cut through my 2" foam, I set up my job size as being 2.25 thick. I'm thinking this
will enable my ball nose to cut through into the spoilboard about .2", which should give me a clean cut through.

However, when I ran the preview I noticed that the 1/2" end mill I'm using for clearance doesn't cut beyond the
perimeter, and the 3/8 ball nose bit is actually making the last cuts in the full depth of the material. That will be
a problem because my ball nose bit only has a cutting edge of 1.5"

I did a quick search and found that ball nose bits with a cutting edge length of 2.5" are 3/4" diameter, and run about $300...

So now I'm wondering if there's a way to make my 1/2" end mill do the clearance cut a little wider so my 3/8
ball nose can finish the profile with just the tip... Any suggestions?

[gkas]

I Added a first Step - Widen Cut. I used an allowance offset of -0.25 and cut another outside cut with a -0.5" bit. Adding the extra material thickness make it tough to see the results of the cuts. I reset it to 2". Trust the preview. Now your 0.5" bit will widen the cut.

Elipse test 1 15w x 10h x 2 thick 3D preview (1).zip

Zipped the crv file to compress

(714.92 KiB) Downloaded 3 times

[duster]

Ok, I think I get it... except for how do you get the widen cut? I don't see that in the moulding toolpath commands.