V-Grooving Stone
- Leo
- Vectric Wizard
- Posts: 4082
- Joined: Sat Jul 14, 2007 3:02 am
- Model of CNC Machine: 1300 x 1300 x 254 Chinese Made
- Location: East Freetown, Ma.
- Contact:
V-Grooving Stone
I have a potential job to "V-Groove" a compass rose into a Blue Stone paver for a customer.
I see some diamond impregnated rotary cutters out there.
Does anybody have experience v-grooving in stone?
I see some diamond impregnated rotary cutters out there.
Does anybody have experience v-grooving in stone?
Imagine the Possibilities of a Creative mind, combined with the functionality of CNC
- dwilli9013
- Vectric Wizard
- Posts: 1237
- Joined: Mon Sep 30, 2013 12:45 am
- Model of CNC Machine: 3 axis Self Designed Self Built
- Location: Machesney Park Illinois
Re: V-Grooving Stone
Seems I remember a while back in a post someone was cutting pavers on their CNC. I guess the biggest issue was the dust goes everywhere.
I would suspect the rigidity of your machine would play a major role as well.
I myself have been wondering how a Marble tile may come out with a diamond drag bit engraving.
Just not ready to thrash my drag bit yet with a try.
I would suspect the rigidity of your machine would play a major role as well.
I myself have been wondering how a Marble tile may come out with a diamond drag bit engraving.
Just not ready to thrash my drag bit yet with a try.
D-Dub
Dwayne
Dwilli
Dwayne
Dwilli
- Rcnewcomb
- Vectric Archimage
- Posts: 5887
- Joined: Fri Nov 04, 2005 5:54 am
- Model of CNC Machine: 24x36 GCnC/WinCNC with ATC
- Location: San Jose, California, USA
- Contact:
Re: V-Grooving Stone
Marble V-Carves very nicely.Marble tile
- Randall Newcomb
10 fingers in, 10 fingers out, another good day in the shop
10 fingers in, 10 fingers out, another good day in the shop
- dwilli9013
- Vectric Wizard
- Posts: 1237
- Joined: Mon Sep 30, 2013 12:45 am
- Model of CNC Machine: 3 axis Self Designed Self Built
- Location: Machesney Park Illinois
Re: V-Grooving Stone
Thanks Randall,Rcnewcomb wrote:Marble V-Carves very nicely.Marble tile
Was that done with a carbide V-Bit? Also feeds & Speeds if you recall.
Thanks
D-Dub
Dwayne
Dwilli
Dwayne
Dwilli
- Rcnewcomb
- Vectric Archimage
- Posts: 5887
- Joined: Fri Nov 04, 2005 5:54 am
- Model of CNC Machine: 24x36 GCnC/WinCNC with ATC
- Location: San Jose, California, USA
- Contact:
Re: V-Grooving Stone
This particular piece was cut with the following settings:
PC router at 13,000 (I'd like to run slower but the PC loses too much torque at 10,000)
Feed and plunge rates of 0.1 ips (6 ipm) -- I have gone as fast as 1ips (60 ipm) on other pieces of stone. I'm sure I could have used faster feed rates if I had a better hold down system at the time. Back then I screwed down scrap wood around the marble to hold it in place. I later moved to vacuum pods.
Bit:
I used a Sears craftsman 1/2" V90. Now I'm inclined to use a CMT 3/4" V90 or 1/2" V60. I use a Gerber 1.25" V120 for some applications but haven't tried it with stone yet.
Cooling:
I held a shop vacuum nozzle near the bit which kept lots of air moving. The bit and collet were warm but not hot at the end of the run.
PC router at 13,000 (I'd like to run slower but the PC loses too much torque at 10,000)
Feed and plunge rates of 0.1 ips (6 ipm) -- I have gone as fast as 1ips (60 ipm) on other pieces of stone. I'm sure I could have used faster feed rates if I had a better hold down system at the time. Back then I screwed down scrap wood around the marble to hold it in place. I later moved to vacuum pods.
Bit:
I used a Sears craftsman 1/2" V90. Now I'm inclined to use a CMT 3/4" V90 or 1/2" V60. I use a Gerber 1.25" V120 for some applications but haven't tried it with stone yet.
Cooling:
I held a shop vacuum nozzle near the bit which kept lots of air moving. The bit and collet were warm but not hot at the end of the run.
- Randall Newcomb
10 fingers in, 10 fingers out, another good day in the shop
10 fingers in, 10 fingers out, another good day in the shop
- dwilli9013
- Vectric Wizard
- Posts: 1237
- Joined: Mon Sep 30, 2013 12:45 am
- Model of CNC Machine: 3 axis Self Designed Self Built
- Location: Machesney Park Illinois
Re: V-Grooving Stone
Thanks Randall.
Sorry Leo I wasn't intending to hijack your thread.
Sorry Leo I wasn't intending to hijack your thread.
D-Dub
Dwayne
Dwilli
Dwayne
Dwilli
- Leo
- Vectric Wizard
- Posts: 4082
- Joined: Sat Jul 14, 2007 3:02 am
- Model of CNC Machine: 1300 x 1300 x 254 Chinese Made
- Location: East Freetown, Ma.
- Contact:
Re: V-Grooving Stone
Don't be sorry.
I am thankful to be generating discussion about it.
Has anybody used anything like this
I have used Carbide to cut marble before.
I am thankful to be generating discussion about it.
Has anybody used anything like this
I have used Carbide to cut marble before.
Imagine the Possibilities of a Creative mind, combined with the functionality of CNC
-
- Vectric Craftsman
- Posts: 201
- Joined: Fri Oct 31, 2014 8:14 am
- Model of CNC Machine: TS1325
Re: V-Grooving Stone
Hello Vectric,
Kindly let me know if my CNC for wood can also engrave on Marble and other material.
If yes this would be so so good.
Kind regards
Jane
Kindly let me know if my CNC for wood can also engrave on Marble and other material.
If yes this would be so so good.
Kind regards
Jane
-
- Vectric Craftsman
- Posts: 201
- Joined: Fri Oct 31, 2014 8:14 am
- Model of CNC Machine: TS1325
Re: V-Grooving Stone
Rcnewcomb wrote:Marble V-Carves very nicely.Marble tile
Hello Randall,
Could you kindly let me know where you got this file from.
Thank you
Jane
- Rcnewcomb
- Vectric Archimage
- Posts: 5887
- Joined: Fri Nov 04, 2005 5:54 am
- Model of CNC Machine: 24x36 GCnC/WinCNC with ATC
- Location: San Jose, California, USA
- Contact:
Re: V-Grooving Stone
Regarding Leo's original question regarding paver stones, I don't have any experience with those.
V-Carving on Marble, limestone, or soapstone can be done with a router that can handle hardwoods. No special bits or cooling is required. Regular carbide bits work fine. Slow the feedrate down a bit from what you would normally use with a dense hardwood. Keep your pass depth fairly shallow.Kindly let me know if my CNC for wood can also engrave on Marble and other material.
It is from the VectorArt.com Mega Collection #1, Image ID: 32809L You can purchase the individual file from them for $2.Could you kindly let me know where you got this file from.
- Randall Newcomb
10 fingers in, 10 fingers out, another good day in the shop
10 fingers in, 10 fingers out, another good day in the shop
- Leo
- Vectric Wizard
- Posts: 4082
- Joined: Sat Jul 14, 2007 3:02 am
- Model of CNC Machine: 1300 x 1300 x 254 Chinese Made
- Location: East Freetown, Ma.
- Contact:
Re: V-Grooving Stone
Jane,
I have cut Marble with a Carbide V-Groove Cutter and is worked - OK, but the process was very slow and it really beat up the cutter.
The job I am asking about now is stone and a much larger project. I will be cutting into a stone 24 x 24 x 2" thick.
I have cut Marble with a Carbide V-Groove Cutter and is worked - OK, but the process was very slow and it really beat up the cutter.
The job I am asking about now is stone and a much larger project. I will be cutting into a stone 24 x 24 x 2" thick.
Imagine the Possibilities of a Creative mind, combined with the functionality of CNC
-
- Vectric Craftsman
- Posts: 181
- Joined: Thu Oct 14, 2010 2:40 pm
- Model of CNC Machine: Hybrid re-build
- Location: Derbyshire UK
Re: V-Grooving Stone
Leo,
Stone is more abrasive than marble what I do is grind my own cutters and use a 3 face \/ cutter 15 deg to 60 deg use plenty of water to wash away the dust to keep a clean cutting edge so it's not re-grinding the dust again, you would need to be cutting slowly DOC I work on 5mm you will tell from the sound the machine is making when you are about right for FPS as stone varies in density/hardness.
The test piece image shows the amount of dust washed out so if the machine is your pride and joy and not use to the amount of abuse or water you will put on it I would be careful.
Phill
Stone is more abrasive than marble what I do is grind my own cutters and use a 3 face \/ cutter 15 deg to 60 deg use plenty of water to wash away the dust to keep a clean cutting edge so it's not re-grinding the dust again, you would need to be cutting slowly DOC I work on 5mm you will tell from the sound the machine is making when you are about right for FPS as stone varies in density/hardness.
The test piece image shows the amount of dust washed out so if the machine is your pride and joy and not use to the amount of abuse or water you will put on it I would be careful.
Phill
A person who works with his hands, his brain and his heart is an artist"
—Louis Nizer
—Louis Nizer
- Leo
- Vectric Wizard
- Posts: 4082
- Joined: Sat Jul 14, 2007 3:02 am
- Model of CNC Machine: 1300 x 1300 x 254 Chinese Made
- Location: East Freetown, Ma.
- Contact:
Re: V-Grooving Stone
Phil - PERFECT - this is what I need to know.
Are you using carbide cutters?
What you are grinding for 3 face cutters - Carbide?
Are you using High RPM - or Low RPM on the spindle?
I will need to make some kind of water tank to capture the slurry and protect the machine.
Thank you
Do you have any further recommendations?
Are you using carbide cutters?
What you are grinding for 3 face cutters - Carbide?
Are you using High RPM - or Low RPM on the spindle?
I will need to make some kind of water tank to capture the slurry and protect the machine.
Thank you
Do you have any further recommendations?
Imagine the Possibilities of a Creative mind, combined with the functionality of CNC
- Leo
- Vectric Wizard
- Posts: 4082
- Joined: Sat Jul 14, 2007 3:02 am
- Model of CNC Machine: 1300 x 1300 x 254 Chinese Made
- Location: East Freetown, Ma.
- Contact:
Re: V-Grooving Stone
I had a dremel tool carbide burr. Not the highest quality cutter, 1/8 shank. I called it a 1/8 ball nosed cutter.
I set 10,000 RPM on the spindle and feedrate at 10 IMP DOC at .01
I used a spray bottle with water and stream. Depth into stone 1/16. Just made sure the stone was well and puddles around the cutter.
I cut a small oval and it looked great.
I that tries 3 letters. The cutter failed on on letter #2 about 80% through.
I have a LOT of different cutter variations on order both Diamond impregnated and carbide blade.
At this point I am confident that cutting stone is certainly a do-able thing to do.
I set 10,000 RPM on the spindle and feedrate at 10 IMP DOC at .01
I used a spray bottle with water and stream. Depth into stone 1/16. Just made sure the stone was well and puddles around the cutter.
I cut a small oval and it looked great.
I that tries 3 letters. The cutter failed on on letter #2 about 80% through.
I have a LOT of different cutter variations on order both Diamond impregnated and carbide blade.
At this point I am confident that cutting stone is certainly a do-able thing to do.
Imagine the Possibilities of a Creative mind, combined with the functionality of CNC
-
- Vectric Craftsman
- Posts: 181
- Joined: Thu Oct 14, 2010 2:40 pm
- Model of CNC Machine: Hybrid re-build
- Location: Derbyshire UK
Re: V-Grooving Stone
Hi Leo,
Sorry it took a while to get back , you found out the normal cutters soon wear out because they are too sharp for stone, I buy in carbide rod to shape up either radius end or V and grind 3 faces into them grinding them to get very little back relief making for a stronger cutting edge that does not rub off too quickly, normal carbide cutters cut work fine in marbles and resinbonds but stone needs that little bit more if you have a lot to cut then you might look at PCD (diamond)
Phill
Sorry it took a while to get back , you found out the normal cutters soon wear out because they are too sharp for stone, I buy in carbide rod to shape up either radius end or V and grind 3 faces into them grinding them to get very little back relief making for a stronger cutting edge that does not rub off too quickly, normal carbide cutters cut work fine in marbles and resinbonds but stone needs that little bit more if you have a lot to cut then you might look at PCD (diamond)
Phill
A person who works with his hands, his brain and his heart is an artist"
—Louis Nizer
—Louis Nizer