Just wondering why - for those with too much time

This forum is for general discussion regarding VCarve Pro
User avatar
Karl60
Posts: 30
Joined: Tue Aug 02, 2011 8:36 pm
Model of CNC Machine: Flat Bed gantry
Location: Perth, UK
Contact:

Just wondering why - for those with too much time

Post by Karl60 »

VCarve 9.510

Why in the attached crv does the top part cut out but not the bottom part?

Clearly there's room for the tool bit - the top cuts out.

Practically, problem simply solved by increasing the vertical space between the parts or turning off separate last past; but that's not the coffee-time query.

Thoughts?

Karl
(gone for a coffee)
Attachments
profile test.crv
(34 KiB) Downloaded 152 times

LittleGreyMan
Vectric Wizard
Posts: 1012
Joined: Fri May 15, 2015 1:10 pm
Model of CNC Machine: 3 axis small size machine
Location: France

Re: Just wondering why - for those with too much time

Post by LittleGreyMan »

Karl,


This has obviously to do with the allowance. In some parts of the curves, the distance between internal curves is about 6.845 < 6.35 (bit Ø) + 0.5 (allowance).

If you calculate separately the toolpath for each vector, it is OK. If you select both, the calculation probably detects there is not enough room for the tool to cut one part without cutting the other one.

But the result is not totally logical as you get a full depth final pass for one of the parts without the first passes.

Better send the file to Vectric.
Best regards

Didier

W7 - Aspire 8.517

User avatar
scottp55
Vectric Wizard
Posts: 4713
Joined: Thu May 09, 2013 11:30 am
Model of CNC Machine: ShopbotDesktop 5.5"Z/spindle/VCP11.5
Location: Kennebunkport, Maine, US

Re: Just wondering why - for those with too much time

Post by scottp55 »

Changed to a Spiral Ramp changing nothing else, and it cut. Hmm...?
scott
Attachments
CHANGED TO SPIRAL RAMP.jpg
profile test SPIRAL RAMP.crv
(58 KiB) Downloaded 130 times
I've learned my lesson well. You can't please everyone,so you have to please yourself
R.N.

LittleGreyMan
Vectric Wizard
Posts: 1012
Joined: Fri May 15, 2015 1:10 pm
Model of CNC Machine: 3 axis small size machine
Location: France

Re: Just wondering why - for those with too much time

Post by LittleGreyMan »

I don' think so, Scott. If I'm not mistaken you only have 1 pass between the parts.

Time for another espresso? :D
Best regards

Didier

W7 - Aspire 8.517

User avatar
scottp55
Vectric Wizard
Posts: 4713
Joined: Thu May 09, 2013 11:30 am
Model of CNC Machine: ShopbotDesktop 5.5"Z/spindle/VCP11.5
Location: Kennebunkport, Maine, US

Re: Just wondering why - for those with too much time

Post by scottp55 »

Right as usual Didier :oops:
Didn't quite slow the cut down enough in preview, OR check toolpath:(
ODD behavior!
(MAYBE another cup:)
I'm claiming distraction on this one...playing with the pedestal, and almost ready to cut Quilted Big Leaf Maple.
scott
Attachments
1 pass center...maybe one more cup.jpg
2018-11-02 08_18_32-VCarve Pro - ShopBot Edition 9.510 {Aloka LLC} - 10.30.18 HEART PEDESTAL 2.jpg
I've learned my lesson well. You can't please everyone,so you have to please yourself
R.N.

joeporter
Vectric Wizard
Posts: 519
Joined: Tue Jul 21, 2009 8:22 pm
Model of CNC Machine: ShopBot Buddy Standard
Location: Marietta, GA.

Re: Just wondering why - for those with too much time

Post by joeporter »

I think you need a separate toolpath for each part...joe

LittleGreyMan
Vectric Wizard
Posts: 1012
Joined: Fri May 15, 2015 1:10 pm
Model of CNC Machine: 3 axis small size machine
Location: France

Re: Just wondering why - for those with too much time

Post by LittleGreyMan »

joeporter wrote:I think you need a separate toolpath for each part...joe
No, if the space between parts is sufficient, the toolpath will be calculated without problem.

If you run 2 toolpath with the original spacing each toolpath will cut a little the other part because of the last pass allowance.
Best regards

Didier

W7 - Aspire 8.517

User avatar
sharkcutup
Vectric Wizard
Posts: 2885
Joined: Sat Mar 26, 2016 3:48 pm
Model of CNC Machine: Shark HD3 Pro Extended Bed with Spindle
Location: U.S.A.

Re: Just wondering why - for those with too much time

Post by sharkcutup »

Change both start points on each section to the top center of each section and re-calculate toolpath.

It cuts the parts out thoroughly but I noticed that the second part the is not necessarily started at the start point. The toolpath reverses direction cuts top section after completing the bottom section.

Here is the file

profile test.crv
(63.5 KiB) Downloaded 116 times


Sharkcutup
V-Carve Pro Tips, Gadget Tips & Videos
YouTube Channel - Sharkcutup CNC
V-Carve Pro 11.554

LittleGreyMan
Vectric Wizard
Posts: 1012
Joined: Fri May 15, 2015 1:10 pm
Model of CNC Machine: 3 axis small size machine
Location: France

Re: Just wondering why - for those with too much time

Post by LittleGreyMan »

Sharkcutup,

In your file, the separate last pass is reset to 0, so the problem disappears. If you set it back to 0.5 mm as in the original file, it won't cut properly.

Whatever you do, if tool Ø + last pass allowance > distance between parts, it won't cut properly which makes sense.

Karl, still not back from coffee? Better take an espresso than a long one. :D
Best regards

Didier

W7 - Aspire 8.517

User avatar
sharkcutup
Vectric Wizard
Posts: 2885
Joined: Sat Mar 26, 2016 3:48 pm
Model of CNC Machine: Shark HD3 Pro Extended Bed with Spindle
Location: U.S.A.

Re: Just wondering why - for those with too much time

Post by sharkcutup »

Sharkcutup,

In your file, the separate last pass is reset to 0, so the problem disappears. If you set it back to 0.5 mm as in the original file, it won't cut properly.

Whatever you do, if tool Ø + last pass allowance > distance between parts, it won't cut properly which makes sense.

Karl, still not back from coffee? Better take an espresso than a long one. :D

And so it did change the setting on its own, good catch LittleGreymen for I did not see it change, Thank You. So the problem remains unchanged!

I will take the Espresso, Thank You!!!

Sharkcutup
V-Carve Pro Tips, Gadget Tips & Videos
YouTube Channel - Sharkcutup CNC
V-Carve Pro 11.554

User avatar
Karl60
Posts: 30
Joined: Tue Aug 02, 2011 8:36 pm
Model of CNC Machine: Flat Bed gantry
Location: Perth, UK
Contact:

Re: Just wondering why - for those with too much time

Post by Karl60 »

Back from coffee ....

As far as I can see; the query remains a mystery. It's not a practical problem per se - just a curiosity. Just seemed logical to use a 7mm gap (nice round number) to run a 6.35mm bit up and down. We'll upgrade to 8mm gaps; bigger is surely better.

Onwards.

Thanks.

Karl

LittleGreyMan
Vectric Wizard
Posts: 1012
Joined: Fri May 15, 2015 1:10 pm
Model of CNC Machine: 3 axis small size machine
Location: France

Re: Just wondering why - for those with too much time

Post by LittleGreyMan »

Karl60 wrote:Just seemed logical to use a 7mm gap (nice round number) to run a 6.35mm bit up and down.
Yes, but you have a last pass allowance and the gap is less than 7mm in the curved part.
profile test.jpg
6.35 + 0.5 (allowance)= 6.85 > 6.839

There is not enough space for the bit before the last pass.

But the toolpath is not correct and you'd better send the file to Vectric.

(and take another coffee as I already mentioned that in my first reply :D )
Best regards

Didier

W7 - Aspire 8.517

gregk
Vectric Staff
Posts: 373
Joined: Mon Mar 05, 2018 12:34 pm
Model of CNC Machine: None

Re: Just wondering why - for those with too much time

Post by gregk »

In addition to what LGM explained, it is worth noting that the allowance is applied to both vectors. So, the correct gap between the vectors have to be at least 6.35 mm + 0.5 mm + 0.5 mm = 7.35 mm

I will see whether we can display a useful error message in such case and fail to calculate the toolpath, rather than end up with a wrong toolpath.

Greg K

LittleGreyMan
Vectric Wizard
Posts: 1012
Joined: Fri May 15, 2015 1:10 pm
Model of CNC Machine: 3 axis small size machine
Location: France

Re: Just wondering why - for those with too much time

Post by LittleGreyMan »

Thanks for the feedback, Greg.

I gave a try with a much larger gap, so I didn't notice the double allowance thing.

Karl, back from coffee? :D
Best regards

Didier

W7 - Aspire 8.517

User avatar
mezalick
Vectric Wizard
Posts: 2970
Joined: Mon Nov 03, 2008 9:07 am
Model of CNC Machine: Camaster Cobra
Location: Philadelphia, PA USA
Contact:

Re: Just wondering why - for those with too much time

Post by mezalick »

Just to revisit this..

24" x 24" material work space.
12" diameter circle position in the center of the work space.
Profile toolpath, cutting on the outside of the vector.

Last Pass Allowance of 0.08" will calculate.

Last Pass Allowance of 0.09" will not.

Michael
Michael Mezalick
https://www.youtube.com/user/mezalick
mm@mezalick.com

Post Reply