Bevel the end of a part
- gkas
- Vectric Wizard
- Posts: 1450
- Joined: Sun Jan 01, 2017 3:39 am
- Model of CNC Machine: Aspire, Axiom AR8 Pro+, Axiom 4.2W Laser
- Location: Southern California
Bevel the end of a part
I'm pretty new at Vcarve Pro, about a week. My latest challenge was to bevel the end of a part. In this case a clamp. I got it done using fluting, after reading about the technique on this forum. It works great, but very slow to carve. I tried the chamfer gadget, but I can't figure out how to get it to bevel a single edge, and in a specified direction. After watching the Dovetails Gadget demo, I noticed how the pins bevel is cut. I have no idea how that was done. Can someone point me in the best directions?
- mike.davison
- Posts: 40
- Joined: Mon Oct 05, 2015 2:18 am
- Model of CNC Machine: CAMaster Stinger II with rotary
- Location: Bolton, MA USA
- Contact:
Re: Bevel the end of a part
This may be one of those cases where a table saw or some other conventional woodworking machine is faster. Something to consider.
If the slope matches that of a V bit or of some other profile router bit/cutter you could do a very simple profile cut.
Any chance you could create a jig to hold the board on edge and then mill the slope with an end mill? Pretty fast if you can access the board that way.
Otherwise..... a 3D model using the biggest round nose bit you have.
If the slope matches that of a V bit or of some other profile router bit/cutter you could do a very simple profile cut.
Any chance you could create a jig to hold the board on edge and then mill the slope with an end mill? Pretty fast if you can access the board that way.
Otherwise..... a 3D model using the biggest round nose bit you have.
- mezalick
- Vectric Wizard
- Posts: 2970
- Joined: Mon Nov 03, 2008 9:07 am
- Model of CNC Machine: Camaster Cobra
- Location: Philadelphia, PA USA
- Contact:
Re: Bevel the end of a part
Create a series of vectors and use the fluting toolpath option
Michael
Michael
Michael Mezalick
https://www.youtube.com/user/mezalick
mm@mezalick.com
https://www.youtube.com/user/mezalick
mm@mezalick.com
- gkas
- Vectric Wizard
- Posts: 1450
- Joined: Sun Jan 01, 2017 3:39 am
- Model of CNC Machine: Aspire, Axiom AR8 Pro+, Axiom 4.2W Laser
- Location: Southern California
Re: Bevel the end of a part
That's what I have in my example. I've already cut a part to test it. The dovetail bevel looks like a much faster cut.
- scottp55
- Vectric Wizard
- Posts: 4713
- Joined: Thu May 09, 2013 11:30 am
- Model of CNC Machine: ShopbotDesktop 5.5"Z/spindle/VCP11.5
- Location: Kennebunkport, Maine, US
Re: Bevel the end of a part
If you create only 2 lines, and reverse the start point of the second one in Node edit, and THEN linear array that pair of lines, it will reduce cutting time by almost half due to less air time. Keeping Z1 and Z2 as low as practical for your set up will also help.
scott
OH...don't forget to check the "use vector start points" do not optimize box.
scott
OH...don't forget to check the "use vector start points" do not optimize box.
I've learned my lesson well. You can't please everyone,so you have to please yourself
R.N.
R.N.
-
- Vectric Wizard
- Posts: 1701
- Joined: Sun Sep 23, 2012 12:14 pm
- Model of CNC Machine: CNC Shark Pro, Probotix Meteor 25" x 50"
Re: Bevel the end of a part
You can use the Moulding toolpath. It will cut going back and forth, side to side down the slope without lifting up the bit. Draw a side view (profile) of the slope you want. Start it on the high end. Draw a straight vector (guide rail) along the top from edge to edge. With the guide rail vector selected choose the moulding tool path on the tool path menu side. Tell it to use what you have selected. Then click on the profile vector. Pick a ball end bit. Such a simple slope I'd choose a 1/4" ball end for quickest results. Set a boundary offset to 1/2 the diameter of the bell end bit you've chosen.
4D
4D
- martin54
- Vectric Archimage
- Posts: 7339
- Joined: Fri Nov 09, 2012 2:12 pm
- Model of CNC Machine: Gerber 48, Triac PC, Isel fixed gantry
- Location: Kirkcaldy, Scotland
Re: Bevel the end of a part
I am with Mike on this one, not really a cnc job, I do those on the disk sander. Only takes a few seconds per clamp & it probably won't be long before you cut the end of it off with a tool bit anyway
- gkas
- Vectric Wizard
- Posts: 1450
- Joined: Sun Jan 01, 2017 3:39 am
- Model of CNC Machine: Aspire, Axiom AR8 Pro+, Axiom 4.2W Laser
- Location: Southern California
Re: Bevel the end of a part
This has been mostly an exercise in getting used to the software. I usually do the ends on my belt sander. This started after I read on the forum the ingenious ways fluting was being used. I'm loving this software.martin54 wrote:I am with Mike on this one, not really a cnc job, I do those on the disk sander. Only takes a few seconds per clamp & it probably won't be long before you cut the end of it off with a tool bit anyway
- martin54
- Vectric Archimage
- Posts: 7339
- Joined: Fri Nov 09, 2012 2:12 pm
- Model of CNC Machine: Gerber 48, Triac PC, Isel fixed gantry
- Location: Kirkcaldy, Scotland
Re: Bevel the end of a part
If you are working on getting use to the software then one really good aspect of it is the preview screen, gives a very good view of what the piece will look like once it has been machined, saves a lot of time & money by eliminating mistakes, saved me a few times
It's very easy to forget you have other tools & equipment once you start using a cnc which is why I mentioned the sander, been guilty of it myself in the past
It's very easy to forget you have other tools & equipment once you start using a cnc which is why I mentioned the sander, been guilty of it myself in the past
-
- Vectric Wizard
- Posts: 1701
- Joined: Sun Sep 23, 2012 12:14 pm
- Model of CNC Machine: CNC Shark Pro, Probotix Meteor 25" x 50"
Re: Bevel the end of a part
Bored again. Thought I'd show an example of doing the ramp with the Moulding toolpath. File attached.
4D- Attachments
-
- 20 degree ramp.crv
- (109 KiB) Downloaded 234 times
- gkas
- Vectric Wizard
- Posts: 1450
- Joined: Sun Jan 01, 2017 3:39 am
- Model of CNC Machine: Aspire, Axiom AR8 Pro+, Axiom 4.2W Laser
- Location: Southern California
Re: Bevel the end of a part
Thanks for the example. I've been choosing the selections in the wrong order! No wonder I couldn't get it to work.4DThinker wrote:Bored again. Thought I'd show an example of doing the ramp with the Moulding toolpath. File attached.4D
Thanks everyone for your input. The amount of experienced users in this forum is amazing. I'm sure I'll have more questions.
Gerry
- scottp55
- Vectric Wizard
- Posts: 4713
- Joined: Thu May 09, 2013 11:30 am
- Model of CNC Machine: ShopbotDesktop 5.5"Z/spindle/VCP11.5
- Location: Kennebunkport, Maine, US
Re: Bevel the end of a part
Thanks for that also 4D....Good to look at during first cup in the morning:)
scott
scott
I've learned my lesson well. You can't please everyone,so you have to please yourself
R.N.
R.N.
- FixitMike
- Vectric Wizard
- Posts: 2173
- Joined: Sun Apr 17, 2011 5:21 am
- Model of CNC Machine: Shark Pro Plus (retired)
- Location: Burien, WA USA
Re: Bevel the end of a part
If you use the fluting toolpath to make a bevel with a low slope, an end mill will make a smoother cut than a ball end bit. If the length of the bevel needs to be precise, the guide lines need to be longer on the downhilll end by half the bit diameter as they control how far the center of the bit moves rather than the length of the cut. It doesn't work to change the start end of every other line to save time, as then half the cuts will be up and half will be down.
Good judgement comes from experience.
Experience comes from bad judgement.
Experience comes from bad judgement.
-
- Vectric Wizard
- Posts: 1701
- Joined: Sun Sep 23, 2012 12:14 pm
- Model of CNC Machine: CNC Shark Pro, Probotix Meteor 25" x 50"
Re: Bevel the end of a part
I've found I can get the same results using either the moulding toolpath and a ball end bit, a fluting toolpath with an end mill or a ball end bit. In fluting the vectors all need to be the same length as the bevel is in the top view (run). Slope is generated when you set the depth (rise). Rise over run = slope. The difference in using an end mill or a ball end bit is just in how much in front of the bevel you shift the line array. End mills get shifted by 1/2 their diameter. Ball end bits get shifted over and down by an amount that depends on the slope and diameter of the bit. You set a start depth a little below the surface when using a ball end bit. In both cases the goal is to have the tail end of the bit as it runs down the slope be right where you want the slope face. To get fluting array tool paths as smooth as you can get a moulding or 3D toolpath you just need to have the vectors the same distance apart as the stepover would be for the ball end bit you would have used. Fluting can be optimized by setting the pass depth of the bit used 1/2 or the whole depth you are cutting. Since stepover is small the bit is only stressed on the first plunge which I usually slow down manually using the control software.
I get perfect results by always drawing a side view of the slope line though my material to see where the side view of the bit used needed to start.
4D
I get perfect results by always drawing a side view of the slope line though my material to see where the side view of the bit used needed to start.
4D
- scottp55
- Vectric Wizard
- Posts: 4713
- Joined: Thu May 09, 2013 11:30 am
- Model of CNC Machine: ShopbotDesktop 5.5"Z/spindle/VCP11.5
- Location: Kennebunkport, Maine, US
Re: Bevel the end of a part
Thanks for pointing out my mistake Mike!
I'd been doing troughs for displays using linear and circular arrays, and just spaced it when I answered
I too loved the fluting toolpath:)
scott
I'd been doing troughs for displays using linear and circular arrays, and just spaced it when I answered
I too loved the fluting toolpath:)
scott
I've learned my lesson well. You can't please everyone,so you have to please yourself
R.N.
R.N.